Sawing or milling grooves, rebates and mitres: how do I set this up in imos iX and CAM iX?
Let CAM iX choose between sawing and milling on its own, make rebates reliable and get the right cutting size for mitres, with or without edge banding.
Short answer: In imos iX you draw what you need: a groove, a rebate or a mitre. CAM iX uses machining principles to decide how the machine makes it. Define once what each machine can do; a groove is then sawn, or milled with the largest cutter that fits. For a mitre, choose a mitre angle and a mitre milling profile, and set the edge to edge banding after CNC so imos calculates the cutting size correctly.
Applies to
- imos iX 2017 and later with CAM iX (field experience with 2017, 2019 and 2023)
- Modules: imos iX CAD (Article Designer, edge settings) and imos CAM iX (machine, machining principles, production workflow)
- Integrations: the postprocessor of your CNC machine (e.g. Homag, Biesse or SCM), cutting lists to Ardis or Schnitt, ERP
- Last reviewed: October 2026
Grooves: sawing or milling
- In the machine settings, under Possible operations, define which grooves the machine can make. If the saw unit can only cut in X, allow sawn grooves in X only.
- Create a machining principle that automatically converts a sawn groove in Y into a milling operation.
- Create a milling principle for grooves per cutter, with a condition on groove width. For example: from 8 mm with the 8 mm cutter, from 19 mm with the 19 mm cutter.
- Give the principle with the largest cutter the highest priority and step down by 10. CAM iX then always picks the largest cutter that fits.
- Set sawn grooves to run through the panel at both ends, with an extension of e.g. 10 mm. A sawn groove that stops then deliberately triggers an error.
- For grooves and rebates, set a step depth per pass based on total depth, e.g. with a TAB formula:
<tab(%DE,%DE,4,%DE/2,8,%DE/3,12,%DE/4)>.
Two approaches work well in practice: saw through grooves automatically and mill the rest, or make milling the default. In the latter case, CAM iX converts any sawn groove wider than the smallest cutter into milling. Pick one. Pockets follow the same priority logic; see the article on machining principles.
Rebates
- Create a milling principle for rebates with conditions on width and depth, just as for grooves.
- Draw the rebate on the correct side of the line and check the cutter side in the machine software: the machine preview isn't always right.
- Fix the milling direction. In practice we run grooves and rebates in the same direction as the cutter's rotation, and outer contours in the opposite direction.
- Groove and rebate in a front with a handle profile? Add them as separate operations in the composite panel, driven by variables for depth and width.
Drawing a mitre with the right cutting size
- Select the edges and choose a mitre angle, or set the joint to Mitre in the Article Designer.
- Assign a mitre milling profile to the mitred edge, for example
PRF_VERSTEK. - Set the edge to edge banding after CNC. Without this, the oversize calculation is wrong.
- Use the Filter function to select every mitred edge in the order and set profile and sequence in one go.
- Check the panel size. If you want 2 mm extra on a bare mitre, it has to show in the cutting size: a 600 mm panel is cut at 602 mm.
A banded mitre works differently. Don't choose a mitre profile such as PRF_VERSTEK: imos must include the band thickness, measured along the angle. If the edge bander doesn't pre-mill, use an edge band without oversize. In our tests this worked for doors without a front-gap principle; check other cases first.
Mitres on the CNC or on the panel saw
- Decide per machine whether it makes mitres.
- If the panel saw cuts the mitres, filter the mitre operation out of the CNC's production workflow. The panel keeps its oversize but isn't machined.
- Use a mitre edge band that adds 10 mm oversize automatically. Via cutting list and ERP, the edge bander operator also sees an edge code marking the mitre.
- With several machines, use two mitre profiles, for example
VERSTEK_CNCandVERSTEK_ZAAG. The machine that can't make mitres rejectsVERSTEK_CNCin the workflow, and the panel is routed automatically to the machine that can. - If you mill mitres on panels that already have edge banding, assign left- and right-hand sister tools.
Why this approach?
Designers should draw what the furniture needs, not which tool the machine uses. That knowledge belongs in CAM iX. When a cutter is added, you only adjust the principles. With mitres, everything revolves around the cutting size, because that goes to the cutting list and ERP. So imos must know that the band is applied after CNC, and whether the mitre is bare or banded. We often see mitre profiles stripped out of a workflow entirely. Operations that were needed then quietly disappear too.
Common mistakes
- Sawn groove in Y without a conversion principle. On a machine that only saws in X, you get the 'no machining principle found' message.
- Mitred edge banded before CNC. The oversize, and with it the cutting size, will be wrong.
- Mitre profile plus edge banding. The band isn't included in the size.
- No sister tool assigned. The mitre isn't made with a left/right-hand cutter and the band can tear off.
A Wood Intelligence Plus customer? Then you have access to e-learning courses (in Dutch) on setting up the CAM iX module. They cover everything about creating:
- drilling operations;
- milling operations, such as pocket milling, groove milling, inner contour milling, rebate milling, outer contour milling and format milling along the contour;
- the various sawing operations.
The e-learning videos show you how to draw the operations in iX CAD and how iX CAM runs them on your CNC machine. Read more about Wood Intelligence Plus.
Frequently asked questions
Can a milled groove be made in a single pass, with the lead-in at the end?
Standard principles can't always do that. One solution is a component: a subprogram, created in the machine software, that imos drives with variables.
How do I draw grooves at regular intervals?
Draw them in the Article Designer on the Operations tab. They then become part of the article, so you don't have to draw them per panel.
Why is the cutting size of my mitred panel wrong?
Check three things: is the edge set to edge banding after CNC, is the right mitre profile selected, and for a banded mitre, has the profile been left off?
Further reading
- How do machining principles and formatting classes work together in imos CAM iX?
- How do I read the CAM iX log file and fix 'no machining principle found'?
- Generating cutting lists from imos iX
- Consultancy
More than one solution
Almost every question in this knowledge base has more than one solution. The best fit depends on your workflow, machinery and integrations. Not sure which applies to you, or are you using software we don't (yet) support? Feel free to email Wood Intelligence. We're happy to think along with any challenge.
imos is a trademark of imos AG. Wood Intelligence is an independent consultancy.