Skip to content
Knowledge base

What is a postprocessor and how do I set up a CNC machine in imos CAM iX?

What a postprocessor does and how to set up a CNC machine, machine fields, possible operations and part positioning in imos CAM iX.

Short answer: A postprocessor is software that translates the operations drawn in imos into the program language of your specific CNC machine, for example an .mpr file for Woodwop on a Homag. In CAM iX you then define in the Machine what that machine can do: its machine fields, the possible operations per field and how parts are positioned. The tighter those limits, the sooner imos flags a drawing error instead of producing a wrong program.

Information

Applies to

  • imos iX 2017 and later with CAM iX (also known as PXM)
  • Module: imos CAM iX, with one postprocessor per machine brand
  • Integrations: e.g. Homag (Woodwop), Biesse (bSolid/BiesseWorks), SCM (Xilog/Maestro)
  • Last reviewed: October 2026

What exactly does a postprocessor do?

imos describes a drilling or milling operation in its own machine-independent format. The machine cannot read that. The postprocessor converts the operations into the format your machine control already uses. If your machine runs Woodwop, imos delivers Woodwop-ready files. A few examples:

  • Homag with Woodwop: .mpr files
  • Biesse with bSolid or BiesseWorks: .cix files (or .bpp via batch processing)
  • SCM with Xilog or Maestro: .xxl or .pgmx files, depending on the control

So every machine brand has its own postprocessor. You buy it through your imos reseller and it is activated on your licence.

Step 1: enable CAM iX

On installations that still used the legacy imos CAM (APG), you enable CAM iX in the imos.ini configuration file.

  1. Make a copy of imos.ini in the config folder of your imos installation.
  2. Find the line PXM_ENABLED.
  3. Set the value to 1 (CAM iX only) or 2 (CAM iX and legacy APG programs side by side). 0 means legacy APG only.
  4. Save the file and restart imos.
  5. Repeat this for every imos user in the company.

Step 2: create the machine

  1. In imos CAD or the imos Organizer, open the tree and expand Machines. An empty database only contains the machine standard.
  2. Import the postprocessor installation file.
  3. Name the machine starting with CNC_, followed by brand and type, in capitals. For example CNC_BIESSE_ROVER_A.
  4. Under Class, select the machine software, for example bSolid.
  5. In the machine properties, click Show all properties, select the Target folder field, click Show all properties again and save.
  6. Enter the folder where CNC programs should be written in Target folder, for example \\SRV-FILE\imos\CNC.

Step 3: machine fields and possible operations

A machine field is a fixed stop position on the machine. A drilling centre such as a Homag BHX often has a single field; a nesting machine or Rover has several, sometimes mirrored. Ask your operator or machine supplier for the properties of each field.

  1. Use the + sign to add a row per field. Enter the field number as the Name and a description as the Comment.
  2. Enter the minimum and maximum part sizes per field and indicate whether it is a mirrored field.
  3. Open the first field and click + under Possible operations. The new row defaults to Inner contour.
  4. Change the operation from the drop-down list, for example to Vertical drilling.
  5. Under Orientation, set the direction the operation may come from, for example vertical drilling from the top only.
  6. Add conditions where needed, for example horizontal drilling only with an 8 mm diameter.
  7. Repeat for every operation the machine can actually perform.
  8. Use the arrow icons to set the machining order: if drilling sits above milling, the machine drills first.
  9. If a second field can do exactly the same, link it to the first. This copies the possible operations and positioning criteria in one go.

An example for a 2.5-axis machine: horizontal and vertical drilling, milling and sawing are enabled, but angled (universal) drilling is not. If someone draws an angled hole anyway, CAM iX reports it.

Tip

Start with one machine field and a minimal set of operations. Once the basics work, expand. Add conditional field selection (for example by part size or element name) only after the rest of the setup is in place.

Step 4: part positioning

Besides the possible operations, you define per field how a part is placed on the machine. In practice we use a fixed order of preference:

  1. Set the first condition so that edge 1 (usually the edge-banded side) lies against the stop. This keeps end-face drilling coming from the same direction as much as possible.
  2. Limit that condition, for example: Y size at most 1250 mm and Y no more than 1.5 times X. A part much deeper than it is long becomes unstable.
  3. As a fallback, set the condition longest dimension in X direction for parts where edge 1 cannot go against the stop.
  4. Optionally send small parts to the front field (for example up to 700 mm deep) and larger parts to the rear. It saves the operator reaching.
  5. For near-square parts, use a ratio condition so a difference of a few millimetres does not decide whether the part is rotated.

Why this approach?

CAM iX is only as good as the limits you set. If everything is allowed, imos will happily create a program for an operation the machine cannot do, and the operator finds out at the machine. With the right limits, the designer gets a message straight away. For example: if a mitre is drawn as a saw cut and your machine has no tilting saw, the software must say it cannot be made.

The fixed CNC_ naming keeps the database readable, especially with several machines, and some external packages expect capitals. After sharpening a tool you don't need to change its diameter straight away, because we rely on machine compensation wherever possible.

Frequently asked questions

Do I need a separate postprocessor for each machine?

Per machine brand and control, yes. A Homag with Woodwop needs a different postprocessor than a Biesse with bSolid. The postprocessor is supplied through your imos reseller and activated on your licence.

How many machine fields should I create?

As many as the machine physically has and you actually use. A drilling centre often has one. On machines with several fields we recommend starting with one and linking or extending the others later.

Can I generate programs for several machines at once?

Yes. From imos iX 2019, CAM iX with the multi-workflow module can drive several machines at once. Conditions in the workflow decide which part goes to which machine.

Where do I set speeds and lead-in/lead-out?

Not in the machine, but in the machining principles. The machine defines what is possible; the machining principle defines how it is made.

Further reading

Want to learn CAM iX at your own pace? Wood Intelligence Plus includes a Dutch-language e-learning course for iX CAM.

More than one solution

Almost every question in this knowledge base has more than one solution. The best fit depends on your workflow, machinery and integrations. Not sure which applies to you, or are you using software we don't (yet) support? Feel free to email Wood Intelligence. We're happy to think along with any challenge.

imos is a trademark of imos AG. Wood Intelligence is an independent consultancy.

Download access

Sign in to check whether this download is available.